4.2.1 CYCLE95加工案例

                                             图 毛坯循环应用案例

刀具清单

1)    55°外圆刀：粗车外圆；
2)    35°精车刀：精车外圆；

数控程序

主程序：sub95
N10 G90 G95 F0.2                         ;绝对坐标编程，转进给模式
N20 T1 D1                                      ;调用外圆粗车刀
N30 M03 S1000                            ;主轴正转1000r/min
N40 G00 X60 Z5                            ;刀具到循环起点位置
N50 CYCLE95(“sub95”，2,0.1,0.3,0,0.2,0.1,0,1,0,0,0);调用粗加工循环
N60 G00 X100
N70 Z100                                         ;退回到安全距离
N80 M01                                          ;选择停
N90 T2 D1                                        ;调用外圆精车刀
N100 M03 S1500                            ;主轴正转1500r/min
N110 G00 X100 Z5                          ;刀具定位点
N120 CYCLE95(“sub95”，0,0,0,0,0,0,0.1,5,0,0,1) ;精加工循环
N130 G00 X100
N140 Z100                                        ;退回到安全距离
N150 M30                                         ;程序结束

子程序 sub95.iso
N10 G01 X16 Z2                                    
N20 X20 Z-1
N30 Z-15
N40 X30 CHR=1
N50 Z-20
N60 G02 X30 Z-45 CR=20
N70 G01 Z-50
N80 X40
N90 G03 X50 Z-55 CR=5
N100 G1 Z-65                                       
N110 X60
N120 RET