1.7 The instructions table

D

Tool offset number

Contains offset data for a certain tool T...; D0−> offset values= 0, max. 9 D numbers per tool

D…

F

Feedrate

Path velocity of a tool/workpiece;

unit: mm/min or mm/revolutiondepending on G94 or G95

F…

G

G function

The G functions are divided into G groups. Only one G function of a group can be programmed in a block. A G function can be either modal (until canceled by another function of the same group) or only effective for the block in which it is programmed (non−modal).

G…

G00

Linear interpolation at rapid traverse rate

G00 X… Z…

G01

Linear interpolation at feedrate

G01 X… Z… F…

G02

Circular interpolation CW

center and end points:

G02 X… Z… I… K… F…

radius and end point:

G02 X… Z… CR=…F…

aperture angle and center point:

G02 AR=… I… K… F…

aperture angle and end point:

G02 AR=… X… Z… F…

G03

Circular interpolation CCW

G03…;therwise, as with G2

G33

Thread cutting with constant lead

Cylindrical thread:

G33 Z… K… SF=…

Transversal thread:

G33 X… I… SF=…

Tapered thread; thread lead K

G33 Z… X… K… SF=…

Tapered thread; thread lead I

G33 Z… X… I… SF=…

G04

Dwell time

G04 H…,separate block

G74

Reference point approach

G74 X… Z…,separate block

G75

Fixed−point approach

G75 X… Z…,separate block

G25

Lower spindle speed limitation

G25 X… Z…,separate block

G26

Upper spindle speed limitation

G26 X… Z…,separate block

G17

X/Y plane

G18

Z/X plane

G19

Y/Z plane

G40

Tool radius compensation OFF

G41

Tool radius compensation left of the contour

G42

Tool radius compensation right of the contour

G500

Additional work offset OFF

G501

Additional work offset

G54

1st settable work offset

G55

2nd settable work offset

G56

3rd settable work offset

G57

4th settable work offset

G58

5th settable work offset

G59

6th settable work offset

G53

Settable work offset OFF

G60

Exact stop, modally effective

G64

Continuous−path control mode,

modally effective

G09

Non−modal exact stop

G70

Inch dimension input

G71

Metric dimension data input

G90

Absolute dimension data input

G91

Incremental dimension data input

G94

Feed F in mm/min

G95

Feedrate F in mm/spindle revolutions

G96

Constant cutting rate ON

(F in mm/rev.,  S in m/min)

G96 S… LIM=… F…

G97

Constant cutting rateOFF

WALIMON

Working area limitation ON

Separate block

WALIMOF

Working area limitation OFF

Separate block

DIAMOF

Radius dimension input

Separate block

DIAMON

Diameter dimensioning

Separate block 

H

Dwell time

See G04

I

Interpolation parameters, belongs to the X axis

meaning dependent on G2,G3−> circle center or G33, G34, G35 G331, G332 −> thread lead

See G02,G03 and G33

K

Interpolation parameters,

Belongs to the Z axis; otherwise, as with I

See G02,G03 and G33

M

Miscellaneous function

M…

M00

Programmed stop

Separate block

M01

Optional stop

Separate block

M02

End of program, Can be found in the last block of the processing sequence

Separate block

M03

CW rotation of spindle (for master spindle)

M04

CCW rotation of spindle (for master spindle)

M05

Spindle stop (for master spindle)

M19

Spindle positioning

M19 SP=…,separate block

M30

End of program (as M2)

Separate block

M90

Workpiece number add 1.

Separate block

N

block number subblock

N…

P

Number of subroutine passes

N10 WELLE7() P3

three cycles

R0~R99

R parameters

R1=30

R2=SIN(R1)

RET

Subroutine end

Separate block

S

Spindle speed (master spindle)

Unit of measurement of the spindle r.p.m., when G96 m.p.m

S…

T

Tool number

T…

X

Axis

X…

Z

Axis

Z…

ANG=

Angle for the specification of a straight line for the contour definition. Specified in degrees;  one possibility of specifying a straight line when using G0 or G1 if only one end-point coordinate of the plane is known or if the complete end point is known with contour ranging over several blocks

N10 G01 X… Z…

N20 X… ANG=…

AR=

Aperture angle for circular interpolation

See G02, G03, AR range 0~360

CALL

Indirect cycle call

N10 CALL WELLE7()

Separate block

CHF=

Chamfer;

Inserts a chamfer of the specified chamfer length between two contour blocks

N10 X… Z… CHF=…

N20 X… Z…

CHR=

Chamfer; in the contour definition;

Inserts a chamfer of the specified leg length between two contour blocks

N10 X… Z… CHR=…

N20 X… Z…

CR=

Radius for circular interpolation

See G02, G03

DEF

Definition instruction

Defining a local user variable of the type  BOOL, CHAR, INT, REAL, directly at the beginning of the program

DEF INT VAR1=12

DEF REAL VAR2=2.4

GOTOB

GoBack instruction

N10 LABEL1: …

…

N100 GOTOB LABEL1

GOTOF

GoForward instruction

N10 GOTOF LABEL2

…

N100 LABEL2: …

IF

Jump condition

N10 IF R1>5 GOTOF LABEL3

…

N100 LABEL3: …

LIM=

Upper limit speed of the spindle with G96, G97

See G96

MSG( )

Message text in inverted commas

MSG(“MESSAGE TEXT”)

Separate block

RND=

Rounding

N10 X… Z… RND=…

N20 X… Z…

SET( )

Set values for the variable fields; Various values, from the specified element

See set values for fields

REP( )

Set values for the variable fields; the same value, from the specified element

DEF REAL VAR3[12] = REP(4.5)

all elements value 4.5

SF=

Thread starting point when using G33

See G33,SF range 0~360

SP=

Spindle position when using M19

See M19,Separate block

SPOS=

Spindle position

SPOS= 30

Separate block

TGROUP

Tool group

TGROUP(x)

Separate block

MIRROR

Programmable mirroring

MIRROR X0

Separate block