5.2.9 Reaming 2 (boring 5) CYCLE89

Programming:

CYCLE89 (RTP, RFP, SFD, DEP, RDP, DTB)

Parameters:

RTP

Real

Retraction plane (absolute)

RFP

Real

Reference plane (absolute)

SFD

Real

Safety clearance (enter without sign)

DEP

Real

Final drilling depth (absolute)

RDP

Real

Final drilling depth relative to the reference plane (enter without sign)

DTB

Int

Dwell time at final drilling depth (chip breakage)

 

Fig.5.10 CYCLE89

Function:

The tool drills at the programmed spindle speed and feedrate to the entered final drilling depth. When the final drilling depth is reached, a dwell time can be programmed.

Sequence:

1. Approach of the reference plane brought forward by the safety clearance by using G00

2. Traversing to final drilling depth with G01 and the feedrate programmed prior to the cycle call

3. Dwell time to final drilling depth

4. Retraction up to the reference plane brought forward by the safety clearance using G01 and the same feedrate value

5. Retraction to the retraction plane with G00

Explanation of the parameters:

1. For parameters RTP,RFP,SFD,DEP,RDP, see CYCLE81;

2. DTB(dwell time): The dwell time to the final drilling depth (chip breakage) is programmed under DTB in seconds.

Example:

CYCLE89 is used for reaming 2. The drilling axis is the Z axis. Programming zero point is the center of end face. Dwell time is 1 second.

N10 G00 G90 G17 G40 T1 D1 S400 M03

Specification of technology values

N20 G95 G01 Z10 X0 F0.2

Approach drilling cycles starting position

N30 CYCLE89(10, 0, 1, -20, 20, 1)

Cycle call

N40 G00 Z10

Next position

N50 M02

End of program

0 (0)
Article Rating (No Votes)
Rate this article
Attachments
There are no attachments for this article.
Comments
There are no comments for this article. Be the first to post a comment.
Full Name
Email Address
Security Code Security Code
Related Articles RSS Feed
5.2.1 Drilling, centering CYCLE81
Viewed 13253 times since Fri, Aug 26, 2016
4.2 System parameter
Viewed 3355 times since Fri, Aug 26, 2016
2.6 Work plane G17/G18/G19
Viewed 6314 times since Thu, Aug 25, 2016
3.3 Tool offset table
Viewed 3868 times since Fri, Aug 26, 2016
5.2.8 Drilling with stop 2 (boring 4) CYCLE88
Viewed 1771 times since Fri, Aug 26, 2016
3.1 Tool T
Viewed 1714 times since Fri, Aug 26, 2016
5.3 Turning cycles
Viewed 2030 times since Fri, Aug 26, 2016
1.2 NC program name, structure and content rules
Viewed 2353 times since Thu, Aug 25, 2016
2.2 Dimensions in metric units and inches: G70/G71
Viewed 2027 times since Thu, Aug 25, 2016
6.1 Outer contouring
Viewed 1499 times since Fri, Aug 26, 2016